Ttdfjt

I have designed a lot of 2 layer PCBs so far and am trying to slowly move to 4 layer versions.

One of the major challenges I'm currently facing in that aspect is the acceptable stack up of the layers of the PCB.

I'm currently using the following stack up as I am dealing with a high voltage application.

Could anyone tell me if the stack up I'm going with is accurate? I have attached a screenshot of my current settings in Eagle.

My concern is with the blind vias connecting layers 1-15 and 2-16. Would a pcb manufacturer be able to achieve these interconnects?

The problem is indeed with the crossing 1-15 and 2-16 vias. The manufacturer has to be physically able to make the board. There may be a way to attempt that construction, depending on the equipment the manufacturer has.

There are two straightforward ways to get close to what you have drawn.

1) 1-2 core, drill, thru plate. 15-16 core, drill, thru plate. Assemble, drill, thru plate. That gives 1-2, 15-16, 1-16, but not 1-15 or 2-16

2) 1-2 core, drill, plate. Prepreg 15 foil, drill, plate, prepreg 16 foil, drill, plate. That gives you 1-2, 1-15, 1-16, but not 2-16 or 15-16

More expensive, but I have used the process, micro-vias. It's mainly used for their small footprint, to get tracks between BGA balls.

3) As for (2) but with a final micro-via step which is laser drilling 15-16, power set to ablate the prepreg, but stop at the 15 foil. These vias would be very small and fragile, pads connected to them do not generally survive rework.

4) Speculative. The micro-via process only works because of the small thickness 15-16. It may be possible to micro-via from 16 through to 2, via an aperture etched in 15. Ask the manufacturer. They may have the capability. If you wave money at them, they may be able to develop the capability for you.

5) Speculative. You could replace the 2-16 via with 2-15 and 15-16 micro-vias, if the board vendor was happy to insert another micro-via step in the (3) buildup above.

It would be far better to think harder about your layout, and try to use the standard routes.

Do note that your board construction is unbalanced through the Z direction, this is strongly discouraged by most board vendors. It will probably warp after exposure to soldering heat, cracking your ceramic caps.

Without agreeing that you should do this, it's possible to make all the connections you want using mechanically drilled blind vias. You might find you need to make the diameter of the deeper drills (like layer 1 to layer 15) fairly large to ensure good plating in the via. One vendor I just checked requires an aspect ratio less than 1.0, so you'd have a minimum diameter of about 1.7 mm for those vias (But check with your vendor for their requirements).

You will certainly pay extra for all the additional drilling set-ups required.

Another option that will probably reduce cost and improve the aspect ratio requirement, is controlled-depth back-drilling. In this process, you make a through via, plate it, then drill back to remove the plating from the part of the via you don't want connected.

(image source: multi-cb)

You could then fill the hole with non-conductive epoxy to increase the isolation and prevent contamination getting into the path you're trying to isolate. Caveat: I do not work with high voltages, so if this is meant to provide safety isolation, check with your safety expert whether this process will be accepted as providing the isolation you need.

Alos, asymmetric stack-ups are generally not preferred. Probably your vendor will want you to waive any requirements on board bend and twist.

As others have mentioned, symmetry is very important with PCB stackup, so you should really aim for that. FR4 can withstand 20 kV/mm (according to Wikipedia, you probably want to verify this from the fab). You require 7.4 kV, so it should be more than enough if you make the thickness of 1-2 and 15-16 both 0.8 mm, which would result as a symmetric stackup.

For vias I'd recommend buried via for 2-15 and blind for 1-2 and 15-16. You can then combine one blind and one buried via in the layout to make 1-15 and 2-16. Though buried via for 0.8 mm dielectric can be tricky.